Sets the part copy options you want.

Link To File

Creates an associative link to the file the part copy is created from. When you make changes to the original file, you can update the part copy using the Update Link command on the shortcut menu.

Update Link Options

Displays the Update Model links dialog box so you can specify how you want the part copy updated when the original document is modified.

Copy Colors

Specifies that you want to copy the colors that were used for the original document. For example, you can use the Part Painter command to apply colors to faces and features in the original part or sheet metal document. You can use the Copy Colors option to control whether the colors are copied to the part copy. This option is not available when creating a part copy of an assembly document (.ASM).

Link to Material

Specifies that the part copy is linked to the material specified in the parent document. If the material in the parent document is changed, you can update the link in the child document. This option is useful when creating a part copy of a document where maintaining the material link between the parent and child documents is important. This option is available when the part copy is placed as the base feature. In other words, if other bodies exist in the document before you place the part copy, the Link to Material option is not available.

Use Geometry-based Naming

Specifies that you want to use geometry-based naming when creating a part copy of an X_T document. When you set this option, the faces on the part copy are assigned internal names which can then be used to ensure that the part copy updates properly if the X_T document is changed.

You should set this option when you use the Part Copy command to import models from other systems and want to update the Solid Edge file if changes are made to the imported model. For example, consider the following workflow. Suppose you create a new Solid Edge part file and then use the Part Copy command, with the Use geometry-based naming option selected, to import a model from another system. After you save the Solid Edge part file, you make changes to the source file used as the part copy, Solid Edge can update any changes to the source file. If the option is not set, any features added to the part copy will fail.

Note:

This open works nicely when the model changes are minimal.

Family Of Parts Member

Lists the individual members of the family of parts for the part you are inserting. Select the member name you want from the list. This option is available only if the part you are inserting has had a family of parts defined.

Coordinate System

Positions the part copy with respect to a coordinate system you define. When you set this option you can reposition the part copy by changing the offset values for the coordinate system.

Copy As Design Body

Creates the copy as a design body. When a part copy is placed as a design body, you can add features to the part copy.

Copy As Construction Body

Creates the copy as a construction body. When a part copy is placed as a construction body, you can use it to define the From/To extent when creating another feature. You cannot add features to a part copy placed as a construction element.

Feature Tree List

Displays the list of design and construction bodies in the file from which you are copying. You specify the bodies you want by setting the check mark adjacent to the bodies you want to copy. You can also specify that you want all of the bodies of a certain type copied by setting the check mark adjacent to a body type. For example, if you want to copy all the surface bodies, you can set the check mark adjacent to the Surface Bodies entry.

When you want to copy a select set of bodies into the file, copying all the bodies into the file temporarily makes it easier to find the bodies you want. For example, if you want to copy a select set of surface bodies, first set the Surface Bodies option, then click Apply. This copies all the surface bodies into the file. You can then pause the cursor over each surface body entry in the dialog box and it will highlight in the graphic window. If it is a surface you want, set the check mark. When you have set the check mark for all the individual surfaces you want, clear the check mark for the Surface Bodies entry, then click Apply to update the select set.

Mirror Body

Specifies that you want to mirror the selected bodies about the reference plane you specify. The reference plane you select in the dialog box also highlights in the application window.

Flatten Part

Flattens the part onto the reference plane you select. The reference plane you select in the dialog box also highlights in the application window. This option is available when creating a part copy using a Solid Edge Sheet Metal file (.PSM). If the Link to File option is checked, the flattened copy is associative to the original sheet metal part.

About Top (xy) Plane

Mirrors or flattens the bodies about the Top (xy) reference plane.

About Right (yz) Plane

Mirrors or flattens the bodies about the Right (yz) reference plane.

About Front (xz) Plane

Mirrors or flattens the bodies about the Front (xz) reference plane.

Scale

Specifies how much the software reduces or enlarges the part copy. You can enter different values in the X, Y, and Z boxes if the Uniform Scale box is cleared.

Use Uniform Scale

Scales the part equally in the x, y, and z axes when checked.

Shrink Factor

Sets the shrink factor for the part copy. The value you type should be greater than or equal to 0.00, and less than 1.00. (A value of 0.00 would not enlarge the size of the part and a value of 1.00 is invalid because it would scale the part infinitely.) The value you type in the Shrink Factor box is used to update the X, Y, and Z Scale boxes according to the following equation:

SCALEx,y,z=1/(1-shrink factor)

For example, if you type 0.01 in the Shrink Factor box, the value in the Scale boxes would read 1.0101 and the part would be enlarged by that value.

Apply

Applies the options you have specified. This can be useful when you are copying bodies, but are not sure if the bodies you selected are the bodies you want to copy. You can select a body, then click Apply, and the body is displayed in the graphic window. If you do not want the body, you can deselect the body, then click Apply again.