Specifies the characteristics of occurrences in an assembly.
Displays the Print dialog box so you can print the occurrence properties table to a printer you specify.
Cut
Cuts the current selection and pastes it to the Clipboard.
Copy
Copies the current selection to the Clipboard.
Paste
Inserts the Clipboard contents at the specified insertion point.
Restore
Restores the table to the previous saved configuration. A dialog box is displayed to confirm that you want to discard the changes you have made. The Restore option is not available for changes made to the position of an occurrence.
Translate/Rotate About
Specifies the coordinate system that the origin for an occurrence is based upon. For grounded occurrences or occurrences that have no positioning relationships, you can move or rotate a part by specifying a linear or angular offset value in the x, y, or z axis using the Offset From Assembly Origin columns in the list.
If no user-defined coordinate system exists in the assembly, the only option available is Model Space. If user-defined coordinate systems exist, you can select a coordinate system from the list. You can then type a value in the coordinate columns to move or rotate an occurrence relative to the active coordinate system.
Update Position
Updates the position of the occurrence after you edit its positional or rotational values. The Restore option is not available for this option. You can also use the Enter key to update the positional location of an occurrence without dismissing the dialog box.
Available Columns
The following columns are available in the Occurrence Properties dialog box. You can use the Columns command on the shortcut menu to control the column display and order.
Placement Name
Specifies a name for the occurrence. You can use the Rename command on the shortcut menu to rename the assembly occurrence. You can also rename an occurrence by double-clicking an occurrence in the Placement Name column. When you rename an occurrence, the new name is displayed in the Occurrence Properties dialog box and PathFinder. The actual document name on your computer is not changed.
Note:
The Rename command is unavailable when the Document Name Formula is defined as anything other than Filename.
Item Number
The Item Number column is displayed only when the Maintain item numbers check box is selected on the Item Numbers page (Solid Edge Options dialog box). The item numbers that appear in the assembly Occurrence Properties dialog box are based upon the item numbering schema selected in Solid Edge Options. For example, if the Top level only option is selected, then item numbers are not created for subassemblies.
In the Occurrence Properties dialog box, you can select a cell to edit the item number. The item numbers in edited cells are underlined.
If you enter a number that is already used by a different part or subassembly, the text color in the cell turns red and a popup message notifies you that this is a conflict. You can change the item number using the Next Available Number command on the shortcut menu of that cell.
If you change the item numbering schema in Solid Edge Options, then you can update all item numbers in the Occurrence Properties dialog box using the Reset Item Numbers command on the shortcut menu in this column.
Filename
Displays the name of the file as found on disk.
User-Defined Quantity
Specifies whether a user-defined quantity is specified for a part. When you set the Yes option, you can define a quantity for a part so that it is counted a particular number of times. See Quantity, below, to see how this can be useful.
For non-graphic parts that you have defined custom non-graphic part properties, such as Liters; or As Required, these custom properties are automatically displayed in the cell, and the cell is read-only. For more information, see the Non-graphic Parts in Assemblies Help topic.
Quantity
If User-Defined Quantity is set to Yes, this is where you enter the number of occurrences. This can be useful if you have parts, such as fasteners, which occur numerous times in an assembly, but you placed only once. For example, if you place one bolt in an assembly, but would like the bolt to be counted eight times, you would set a user-defined quantity of eight for the bolt. Using this approach can reduce design time and file size.
The quantity value you specify for the part is counted in the Parts List dialog box when you create a drawing of the assembly. The quantity is determined by collecting the unique parts within the assembly and calculating the quantity values assigned to the part. You will want to use this option if you want a part to be counted a certain number of times in the Parts List dialog box.
You can also set this value to zero, which can be useful for parts in the assembly which are used for reference purposes. They will still be included in a parts list or assembly report, but the quantity value will be zero.
To specify a user-defined quantity of zero for a part, first set the User-Defined Quantity option to Yes. You can then set the Quantity value to 0 (zero).
Note:
Valid values for a user-defined quantity are 0 (zero), and any positive whole number greater than 1. If you set the Quantity value to 1, which is the default value, the User-Defined Quantity option will be set back to No when you click OK.
Offset From Assembly Origin Columns
Specifies a relative location for the selected occurrence. You can define a linear or angular offset value in the x, y, or z axis for grounded occurrences or occurrences that have no positioning relationships.
In some design scenarios, it can be useful to edit these values gradually to incrementally move or rotate an occurrence into position. For example, when you are trying to determine the proper position for an occurrence in a cramped location.
In these situations, you can type a value, then click the Update Position button on the dialog box to relocate the occurrence, without dismissing the dialog box. When you determine the final location, you can click the OK button to dismiss the dialog box. You can also use the Enter key to update the positional location of an occurrence without dismissing the dialog box.
These boxes are read-only for occurrences that are positioned using assembly relationships or linked to an assembly sketch.
X
Sets the linear offset value in the x direction.
Y
Sets the linear offset value in the y direction.
Z
Sets the linear offset value in the z direction.
X degrees
Sets the rotational offset value in the x axis.
Y Degrees
Sets the rotational offset value in the y axis.
Z Degrees
Sets the rotational offset value in the z axis.
Selectable
Controls whether the occurrence can be selected in the graphic window. When you set the Selectable option to No for an occurrence, you can still select it in PathFinder.
Higher Level
Specifies that the occurrence will be displayed when the current assembly is used in a higher level assembly. When set to No, the occurrence is not displayed in higher level assemblies and is not included in parts list in the when the higher level assembly is placed in a draft document.
Reference
Specifies that the occurrence is displayed as a reference part in a drawing view. Reference parts in drawing views are displayed using a different style.
Assembly Reports
Specifies that the occurrence will be included in reports generated for the assembly, such as bills of material and parts list.
Drawing Views
Specifies that the occurrence will be displayed in drawing views created of the assembly in the Draft environment.
Physical Properties
Specifies that the occurrence will be included in physical property calculations of the assembly.
Interference Analysis
Specifies that the occurrence will be included in interference analysis calculations of the assembly.
Linked To:
Displays the name of the assembly to which the part is linked.
Shortcut menu commands
Cut
Cuts the current selection and pastes it to the Clipboard.
Copy
Copies the current selection to the Clipboard.
Paste
Inserts the Clipboard contents at the specified insertion point.
Columns
Displays the Format Columns dialog box so you can set the column display and order options.
By default, all available columns are selected for display in the Occurrence Properties dialog box. You can hide columns, change the column width, and change the column data alignment in the Format Columns dialog box.
Font
Displays the Font dialog box so you can select the font, font style, and font size you want.
Search and Replace
Displays the Replace dialog box so you can find and replace text within the dialog box.
Sort
Allows you to sort the list in ascending or descending order.
Rename
Renames the selection. The selection is renamed within the Occurrence Properties dialog box and PathFinder, but the actual document name on your hard drive is not changed. This command is not available when the Document Name Formula is defined as anything other than Filename.
Reset Default Name
Restores the occurrence name to its default value effectively removing the overridden placement name.
Next Available Number
Renumbers an item in the assembly with the next available item number. Right-click a cell in the Item Number column in the parts list or assembly report to get the next available number.
Reset Item Numbers
Regenerates all item numbers based on the settings on the Item Numbers page (Solid Edge Options dialog box).
Note:
When you reset item numbers, any edits you have made are reset, too.