The Caption tab in the Properties dialog box modifies the caption text and formatting options for a view annotation. The specific options that are available vary with the type of annotation that is selected.

Drawing View style

Specifies the drawing view style to associate with the view annotation caption.

Drawing view styles are mapped to drawing view types and view annotation types on the Drawing View Style tab (Solid Edge Options dialog box).

Caption

The Caption options display and modify the caption content that has been defined for the view annotation in the Caption tab (Drawing View Style dialog box).

Caption

Specifies the content for the currently selected view annotation caption. You can create a caption that contains a single line of plain text, property text, and symbols using the Properties buttons and by typing directly in the box.

Show

Specifies whether the view annotation caption is displayed by default on the source view containing the cutting plane line, viewing plane line, or detail envelope.

Properties buttons

• The View Annotation Name and View Sheet Number buttons insert property text codes, which in turn reference the corresponding definitions in the Properties section at the bottom of the dialog box.

• The Property Text button inserts property text strings that reference other sources.

• The Symbols button inserts property text codes that convert to symbols.

Properties buttons
Use this	To generate this string	To extract this content	Example	From this source
	%VA	View annotation name	A	The content in the View Annotation Name (%VA) Properties box.
	%VN	View sheet number	(2)	The current sheet number where the source view is located.
	%{Author}	Selects and inserts any property text strings associated with the Draft document or the model.	J. Simon	Select Property Text dialog box
	These property text codes: %PM %DI %DG	You can select symbols and values for insertion at the current cursor position in the caption.	Generate these symbols: ± ° ∅	Select Symbols and Values dialog box

Format

The Format options display and modify the appearance of the view annotation caption that has been defined in the Caption Format tab (Drawing View Style dialog box).

Font

Lists the available fonts. Applies the font to the currently selected view annotation caption text.

Font style

Applies Regular, Bold, Italic, or Bold Italic font style to the currently selected view annotation caption text.

Color

Specifies the text color for the currently selected view annotation caption text.

Size

Specifies the text size for the text in the currently selected view annotation caption text.

Properties edit boxes

The Properties boxes define the content that is referenced by the %VA and %VN property text codes when they are inserted in the Caption text box.

View Annotation Name (%VA)

Specifies the alphanumeric characters to use for labeling the view annotation.

The displayed label is system-generated using the automatic naming sequence defined in the Specify Annotation Letters dialog box.

Example:

• Primary labels:

  A

• Appended letters and numbers, which can be regular font or subscript:

  AA - AA

  

• A1 - A1

  

You can edit the label after placement, but only if it is not in Follow defined object sequence mode. Even then, you can override the label definition for a specific view.

To learn more, see Drawing view captions.

Auto

When checked, automatically names the viewing plane line, cutting plane line, or the detail envelope using the naming sequence defined in the Specify Annotation Letters dialog box, and using the order specified in the Define Object Sequence dialog box.

When unchecked, you can edit the label for the currently selected view annotation.

Note:

• This option is checked by default when Follow defined object sequence is selected on the Annotation tab (Solid Edge Options dialog box).

• This option is not available when Follow object creation sequence is selected on the Annotation tab (Solid Edge Options dialog box).

View Sheet Number (%VN)

Specifies the content to display when the view sheet number is shown in the view annotation caption.

Inserts the property text string for the View Sheet Number into the View Sheet Number text box.

The view sheet number is useful when the source view with the view annotation and the derived view—the section, detail, or auxiliary view—are moved to different sheets.

Show

The Show check box is available when a detail envelope, viewing plane line, or cutting plane line is selected. It displays the sheet number where the detail view, auxiliary view, or section view is located when the %VN property text exists in the Caption text box.

Note:

You can use the following check box on the Annotation tab (Solid Edge Options dialog box) to show the sheet number automatically when the views are moved onto different sheets, and to hide the cross-reference when the views are on the same sheet:

• Show sheet number if parent annotation (e.g. cutting plane) and derived view (e.g. section view) do not reside on the same sheet

At

The At list is available when a cutting plane line or a viewing plane line is selected. It specifies where to display the view sheet number, when the Show check box is selected. The options are at the Left Arrow, Right Arrow, or at Both Arrows of the view annotation. The number of lines actually displayed is controlled by the Single or Double setting on the General tab of the Properties dialog box.

Note:

You can specify display location only when the View Direction Lines are set to Double on the General tab (Viewing Plane Properties dialog box).