When placing a parts list on an assembly drawing, you can use the List Control tab to specify the granularity of subassemblies and parts in the parts list.
Global
Specifies how the parts list is generated.
Top-level list (top level and expanded components)
Specifies that only the top level assembly is searched when building the parts list. If the top level assembly contains subassemblies, each subassembly will be listed in the parts list, but the parts within the subassemblies will not be listed.
When this option set, you can use the Subassemblies options to specify how the parts in individual subassemblies are counted.
In the resulting table, the quantity for each occurrence is the total number of times the item is represented in the assembly.
Atomic list (all parts)
Specifies that subassemblies are searched when building the parts list. If the top level assembly contains subassemblies, the parts in the subassemblies are included in the parts list, but the subassemblies are not listed.
In the resulting table, the quantity for each occurrence is the total number of times the item is represented in the assembly.
Exploded list (all parts and subassemblies)
Displays an exploded assembly structure in the parts list. Use this option when you want to show all parts, subassemblies, and subassembly parts in the parts list.
In the resulting table, item quantities are based on ownership. A part may be listed multiple times in the list, once for each subassembly where it is used. The quantity shown in each row is the number of times the item is used by its owner.
Use level based item numbers
When checked, displays level-based item numbers based on ownership within the assembly structure. Each unique subassembly is an owner, and the parts and subassemblies under it receive item numbers based on its level, for example, 1, 1.1, 1.2, 1.3, 2, 3.
You can indent level based item numbers using the Data alignment option on the Columns page.
Note:
Any item may be owned by many different subassemblies. In this case, the same item may receive a different number.
When unchecked, displays flat list item numbers. Flat list item numbers do not indicate ownership.
Example:
For the level-based item numbers 1, 1.1, 1.2, 1.3, 2, 3, the flat list equivalent is 1, 2, 3, 4, 5, 6.
Note:
If you use flat list numbering for an exploded parts list, all components are numbered. This includes the subassemblies, which are the intermediate owners.
Show top assembly in list
Inserts a row in the parts list for the top level assembly name.
Expand weldment subassemblies
Controls how weldment assemblies are treated in a parts list. When you set this option, the parts in a weldment assembly are included in the parts list. When you clear this option, a weldment assembly is treated as a single component. Some companies treat a weldment assembly as a single component for parts list purposes.
Configuration
Specifies an assembly display configuration to control what is displayed in the parts list. Selecting a predefined assembly configuration sets options for how subassemblies are treated in the parts list, what is included and excluded, what is shown or hidden.
The default is No selection.
Selected item
Specifies whether the selected part or subassembly is included in the parts list. The symbol adjacent to the part or subassembly changes color to indicate whether it is included or excluded.
Include
Specifies that the part or assembly is included in the parts list.
Exclude
Specifies that the part or assembly is excluded from the parts list.
Subassemblies
Controls how subassemblies are counted in the parts list.
Include assembly as single item
Specifies that the selected subassembly is counted as one unit in the parts list.
Include assembly components
Specifies that the individual parts in the selected subassembly are itemized in the parts list.
Include all ballooned parts in all drawing views
Specifies that all parts that are ballooned are included in the parts list.
Exclude parts hidden in all drawing views
Specifies that all hidden parts are excluded from the parts list. Also applies to parts that were hidden by clearing the Show option on the Display page of the Drawing View Properties dialog box.
Note:
If a part is shown in any drawing view on any sheet, then it will not be excluded using this option.
Exclude parts marked as reference in all drawing views
Specifies that all reference parts are excluded from the parts list. Reference parts are parts marked as reference on the Display tab of the Drawing View Properties dialog box.
Restore defaults
Resets the exclusion options on this tab. You may want to use this button to restore the default parts list granularity settings when you have made changes using the options in the Selected Item and Subassemblies sections.